HD79476: DRAFTING(INTDRAFT) / CHANGES MADE IN STANDARD IS NOT REFLECTED IN THE DRAWING

APAR status

• Closed as user error.

Error description

• DRAFTING(INTDRAFT) / CHANGES MADE IN
  STANDARD IS NOT REFLECTED IN THE DRAWING
  .
  PROCESS:
  1.Start CATIA V5 in admin mode.
  2. Select Tools / Standards from the contextual
  menu.
  the  Standard Definition dialog box appears.
  3. Select drafting from the dropdown list of
  Category.
  4. Select ISO.xml from the dropdown list of File.
  5. Select ISO / Dress-Up /Symbols /Filled Circle/
  Diameter.
  .
  6. Change the value of Diameter from 2 to 5.
  7. Select ISO / Dress-Up /Symbols /Open Arrow /
  Length.
  8. Change the value of Length from 2 to 5.
  9. Select ISO / Dress-Up /Symbols /Open Arrow /
  Angle.
  10. Change the value of Angle from 30 to 60.
  11. Click Save As New button.
  .
  The  Save As dialog box appears.
  12. Enter test_ISO, and click Save button.
  13. Click OK from the Standard Definition dialog
  box.
  14. Close the CATIA session.
  .
  SCENARIO:
  .
  Case1
  1 .Start CATIA with normal mode.
  2. Create a Drawing with the Standard as test_ISO.
  3. Select Balloon icon
  4. Click any place on the sheet.
  The Balloon Creation dialog box appears.
  5. Click OK button.(Balloon is created.)
  RESULTS:
  The diameter is not changed although the value of
  Diameter is changed to 5 in the Standard.
  This is problem behavior
  .
  Case2
  1. Create a Balloon on the Drawing.
  2.Select the balloon and right click on the
  manipulator.
  the Contextual menu is displayed.
  3. Select Symbol Shape and change it to Open
  Arrow
  RESULTS:
  The open arrow is not displayed with the changed
  value in the standard.
  This is also the problem.
  .
  Case3
  1 .Click Arrow icon icon.
  2 .Click any place on the sheet.
  3. Arrow is created.
  RESULTS:
  The arrow is displayed with the changed made in
  the standard.( this is correct behavior)
  .
  EXPECTED RESULTS:
  The changes made in the standard should be
  reflected in the drawing.
  .
  .
  

Local fix

Problem summary

Problem conclusion

Temporary fix

Comments

• INCIDENT DIAGNOSIS:
  .
  DRAFTING(INTDRAFT) / CHANGES MADE IN
  STANDARD IS NOT REFLECTED IN THE DRAWING .
  EXPLANATION:
  .
  Customization for leaders extremities has to be
  made in another section of the standard file.
  .
  This is mentioned in the Interactive Drafting user
  documentation:
  "Note that symbol parameters apply only to
  arrows, and not to leaders (annotation leaders,
  dimension leaders, etc.). If you want to modify
  dimension and annotation leader symbols, refer to
  the Dimension Parameters > Dimension and
  Annotation Leader Symbols section."
  .
  Correct Application:
  Modify the "Dimension Parameters / Dimension
  and Annotation Leader Symbols" section.
  .
  DOCUMENTATION REFERENCE:
  Interactive Drafting
  Administration Tasks
  Setting Standard Parameters and Styles /
  Dimension Parameter
  .
  

APAR Information

• APAR is sysrouted FROM one or more of the following:

• APAR is sysrouted TO one or more of the following:

Fix information

Applicable component levels